G code: G40, G41, G42, G50, G51, G52, G60, G61, G70, G71
Function: The commands activate preprocessing modules, such as SMC_SmoothPath, SMC_RoundPath, SMC_AvoidLoop, SMC_ToolCorr and SMC_ToolRadiusCorr.
Note
If the option Show preprocessed path is activated, then the edited path is visible in the graphical editor.
Syntax
G40
G41 D
G42 D
G50
G51 D
G52 D
G60
G61
|
G code word |
Description |
|
D |
Tool radius or overlay radius for G51/G52. |
Commands for tool radius compensation
|
G code |
Description |
|
G40 |
Ends tool radius compensation |
|
G41 |
Starts tool radius compensation to the left of the workpiece |
|
G42 |
Starts tool radius compensation to the right of the workpiece |
|
G43 |
Starts tool length compensation. The tool offset to be corrected is specified with the parameters I, J K (for X, Y, Z). The tool length compensation is deactivated by setting the parameters to zero. After activation or deactivation, ramping in or out is performed, respectively. For more details, see SMC_ToolLengthCorr. Note: The length of the tool must not change during an active tool radius compensation because it can cause the path to be broken. |
Commands for angle rounding and angle smoothing
|
G code |
Description |
|
G50 |
Ends the angle rounding and smoothing |
|
G51 |
Stars the angle smoothing by means of SMC_SmoothPath |
|
G52 |
Starts the angle rounding by means of SMC_RoundPath |
|
G70 |
Ends the smoothing of additional axes by means of SMC_SmoothAddAxes |
|
G71 |
Starts the smoothing of additional axes by means of SMC_SmoothAddAxes |
|
G code |
Description |
|
G60 |
Ends the function for loop suppression |
|
G61 |
Starts the function for loop suppression by means of SMC_AvoidLoop |
Example: Angle smoothing
N0 G51 D10 F100
N10 G01 X$g_x$ Y0 F50 E30 E-30
N20 G01 X0 Y$g_y$
N30 G01 X0 Y0
N40 G50
See also
